Thread Turning on Okuma
March 7, 2011, 12:26 pm by Eldar Gerfanov (Admin)
G71 X Z A|I B D U H L E F J M Q
- D=First Depth of Cut
- U=Finish Depth of Cut
- J=Number of threads at F
- X=Target Depth (minor Dia of theread)
- Z=Coord of end Point
- A= Angle of thread
- B= Tool Cut angle
- H= Difference between major and minor dia of the thread
- M= Cut pattern
- M32= Longitudal
- Q= Number of leads
Code
N24 (T5 OD 60DEG CW THREAD TOOL)
N00 G97 G95 S300 M3
N01 G0 X2.1 Z3.05
N02 M8
N03 G0 X1.2
N04 Z0.1538
N05 X0.7
N06 G1 X0.5 F0.076
N08 G71 X0.4 Z-0.8269 D0.01 U0.003 B29. H0.05 F0.077 M32
N09 G0 X1.2 Z-0.8269
N40 Z3.05
N41 X2.1
N00 G97 G95 S300 M3
N01 G0 X2.1 Z3.05
N02 M8
N03 G0 X1.2
N04 Z0.1538
N05 X0.7
N06 G1 X0.5 F0.076
N08 G71 X0.4 Z-0.8269 D0.01 U0.003 B29. H0.05 F0.077 M32
N09 G0 X1.2 Z-0.8269
N40 Z3.05
N41 X2.1
Note: Feed mode must be in G95(IPR)