Renishaw OTS Tool Probe on Haas: Setting diameter wear offset value.January 16, 2012, 8:31 pm
January 16, 2012, 8:31 pm
September 7, 2016, 10:10 pm
Sat August 15, 2009, 4:00 pm
Sat April 22, 2017, 6:56 pm
Renishaw OTS tool probe cycle for HAAS can set both length and diameter offsets.
Too bad there is no choice: it only puts absolute measured diameter of the tool into D- diameter offset and makes wear offset=0
But if your programming is done with the center of the cutter, then you actually only need the difference between actual and programmed diameters of the tool.
I.E.: When probing 5/8Dia end mill, we get D=0.6248. You would normally have to subtract 5/8 from it and leave the -0.0002 difference.
But there is an easier way
Warning:Make sure you know what you are doing.
Make sure you backup all files you are going to modify.
I simply WILL NOT care about any damage done to your machine in any case.
- Go to settings and set protect 9xxx programs from edit to OFF
- Go MEM and edit program O09852 (RENISHAW DIA. SET)
- Go to line N31 and replace
#[ 2400 + #7 ]= #8 / #156
#[ 2400 + #7 ]= [ #8 - #19 ] / #156
- Go to settings and set protect 9xxx programs from edit to ON
Now when you probe tool for diameter, D offset will contain the difference between approximate Dia and actual dia of the tool.